Go Home

[David White]

When I create a series of tool paths on a single part. The bot returns to the home position after each tool path. How can I stop this from happing?
Thanks
Dave White

[Brady Watson]

Comment out the J3,0,0,1 at the end of the SBP file or modify your post processor to eliminate it.

-B

[pkirby]

I have not tried it yet, but I asked Brian from Vectric about it at a recent camp and he said that if I downloaded the new ShopBot Software it should automatically fix that problem. But I have not verified this yet.

[David White]

how would I go about modifing the post processer. I did this in the old PW but i cant remember how to do it.

[Brady Watson]

If you are using PW, you won't be able to modify the post. ArtCAM & Aspire no problem. There is an internal checksum that ensures the output is only for a ShopBot. This is why PartWorks is cheaper than VCarve Pro.

You can manually edit the SBP and ' comment out the line that makes it run home. It is easy...and only takes a second.

-B

[Brian Moran]

Hi,

You can modify the PartWorks post processor, within reason, but it must still be outputting ShopBot compatible code.

Depending on the post you are using there will be a section similar to ...

+---------------------------------------------------
+ Commands output for a new segment - toolpath
+ with same toolnumber but maybe different feedrates
+---------------------------------------------------

begin NEW_SEGMENT

"'Toolpath Name = [TOOLPATH_NAME]"
"'Tool Name = [TOOLNAME]"
"'----------------------------------------------------------------"
+ "'[TOOLPATH_NOTES]"
"'----------------------------------------------------------------"
"TR,[S],1"
"MS,[FC],[FP]"
"J3,[X],[Y],[ZH]"


As Brady mentioned, its the

"J3,[X],[Y],[ZH]"

Line which needs removing. I would still add a JZ,[ZH] just to ensure the tool is at a safe Z height.

There is a guide to editing the post-processors which can be accessed from the Help menu on the current version of PartWorks (V3.5)

Brian

[Brady Watson]

Thanks Brian

-B